Measure a test bend to find effective K

Choose reverse K mode when you have measurements from a test piece. Record thickness t, formed inside radius r, unloaded inside angle β, outside dimensions A and B, and the original blank length L₀. Measure A and B to the intersection of the extended outside faces: the virtual sharp corner. Inside dimensions and straight lengths from bend tangency points need different equations.

Measure the angle after unloading: β = 90° is a right angle, and a more open part has β greater than 90°. The forward mode uses bend rotation α = 180° − β. Use the formed inside radius, which need not equal the punch-tip radius. When a drawing gives an outside radius, subtract the measured thickness to obtain r.

Keep the material grade and condition, batch, measured thickness, rolling direction, tooling and forming method with the result. The inverse result is an effective geometric K for that test setup. For a known K, switch to flat-length mode and enter the same dimensional convention.

Use millimeters, inches and material-specific sheet gauge

Enter lengths in millimeters (mm) or decimal inches (in). Switching units converts the dimensions and results; angles remain in degrees and K remains dimensionless. One inch equals exactly 25.4 mm. NIST: SI units of length.

Select mild steel, stainless steel or aluminum before choosing a gauge. The same gauge number has different nominal thicknesses for different materials. Fractional plate sizes, including 1/8, 3/16, 1/4, 3/8 and 1/2 in, are separate thickness choices, not gauge numbers.

Nominal thickness at 16 gauge

MaterialInchesMillimeters
Mild steel0.0598 in1.51892 mm
Stainless steel0.0625 in1.58750 mm
Aluminum0.0508 in1.29032 mm

Gauge selection fills a nominal thickness. Enter the actual measured thickness when calibrating a test bend. Changing material with a gauge selected changes its nominal thickness; manually entered thickness is a measurement. Material selection controls the thickness lookup, not K. UniPunch: metal gauges.

Use K established for the actual grade, thickness, tooling and process. A material name alone does not establish a production K-factor.

The formed profile shows A, B, t, r and the angle; the neutral layer follows K. The flat diagram divides the blank into left straight length A − s, neutral-layer arc BA and right straight length B − s. Their sum is L₀. The diagrams appear when the required inputs define valid geometry; they show length development, not part width or a compensation angle.

Read allowance, setback, deduction and flat length

The calculator returns four numbers. Bend allowance is the developed length of the neutral axis through the bend zone. Outside setback is the distance from the virtual sharp corner to a bend tangent point along one outside face. Bend deduction is twice outside setback minus bend allowance, and flat length is the two outside legs minus that deduction. It also shows the included angle so a drawing that uses the angle between the legs can be read without a second conversion. This is a one-bend geometric model, not a validated production flat pattern.

Enter the drawing convention and check one bend

Use bend rotation α, with unloaded included angle β = 180° − α. A drawing showing β = 120° therefore needs α = 60°, not 120°. Both outside legs must extend to the virtual sharp corner; tangent straight lengths cannot be entered as those legs. Teaching assumption, not factory measurement: α = 90°, r = 2 mm, t = 2 mm, K = 0.44 and A = B = 100 mm give BA = π/2 × (2 + 0.44 × 2) = 4.5239 mm; setback = (2 + 2) × tan45° = 4 mm; BD = 8 − 4.5239 = 3.4761 mm; flat length = 200 − 3.4761 = 196.5239 mm.

Check angle, radius and outside-leg conventions

  • The bend angle is the rotation applied to the sheet; 90° means a right-angle bend. The included angle is shown as 180° minus the bend angle.
  • Leg A and leg B are outside dimensions measured to the theoretical sharp corner, which is how most drawings dimension a part.
  • The inside radius is entered directly. If the drawing gives an outside radius, subtract the thickness before entering it.
  • The calculation describes one bend. For several bends, accumulate deductions only when each bend contribution and its dimensional convention are clear; this is not an automatic CAD unfold.
  • The result does not include springback compensation, hole deformation or a specific tooling radius correction.

Bend allowance versus bend deduction

Bend allowance describes the arc itself. Bend deduction describes the difference between the outside dimensions and the flat pattern. They are related but not interchangeable: a drawing dimensioned to outside sharp corners is reduced by the bend deduction, while the arc length that replaces the corner during forming is the bend allowance. Mixing the two can produce an incorrect blank size.

For a fuller explanation, read allowance and deduction principles.

K, bend allowance and bend deduction: both directions

K is the distance from the inside face to the neutral layer divided by thickness t. K has no units. BA is the neutral-layer arc length; BD is the length subtracted from the sum of the outside dimensions. The outside setback s is also called OSSB.

The site uses α for bend rotation in degrees and β for the finished inside angle after unloading: α + β = 180°. θ is the same bend rotation in radians. Only at a right angle are α and β both 90°. For β = 120°, use α = 60° in forward mode.

Forward calculation with known K

QuantityEquation
Angle conversionα = 180° − β; θ = α × π / 180
Outside setbacks = OSSB = (r + t) × tan(θ / 2)
Bend allowanceBA = θ × (r + K × t)
Bend deductionBD = 2 × s − BA
Flat lengthL₀ = A + B − BD = (A − s) + BA + (B − s)

Reverse calculation from a measured blank

QuantityEquation
Measured deductionBD = A + B − L₀
Measured allowanceBA = L₀ − (A + B − 2 × s)
Effective KK = (BA / θ − r) / t

All lengths must use the same unit. The calculator computes in mm internally and presents results in the selected unit. This model assumes one bend, a circular bend zone and constant thickness. Hems, rolls, substantial thinning and multi-bend parts need appropriate process models. K = 0.44 is an editable example assumption.

Worked examples: reverse K and calculate flat length

1. Find K from a known blank

Illustrative inputs: t = 2 mm, r = 2 mm, β = 90° (α = 90°), A = 50 mm, B = 30 mm and L₀ = 76.4 mm. Then s = 4 mm, BD = 50 + 30 − 76.4 = 3.6 mm and BA = 8 − 3.6 = 4.4 mm. K = (4.4 / (π/2) − 2) / 2 ≈ 0.4005634992.

2. Calculate a blank with assumed K

Keep t = r = 2 mm, β = 90°, A = 50 mm and B = 30 mm, but separately assume K = 0.44. BA ≈ 4.523893 mm, BD ≈ 3.476107 mm and L₀ ≈ 76.523893 mm. This is a separate demonstration, not a validation of the previous measured blank.

Angle comparison at t = r = 2 mm, A = 50 mm, B = 30 mm and K = 0.44

Inside angle βBend rotation αFlat length L₀ (mm)
60°120°72.175451
90°90°76.523893
120°60°78.397127

The decimals support equation checking; they do not describe manufacturing accuracy. For a non-right-angle bend, both bend rotation and outside setback change.

Measurement sensitivity: if only L₀ changes, ∂K/∂L₀ = 1/(θt). At t = 2 mm and β = 90°, a 0.1 mm change in blank length changes K by about 0.03183. This is a single-variable sensitivity, not an overall uncertainty estimate.

Choose K without a universal material table

K is not a constant owned by a material name. It varies with the actual radius-to-thickness ratio, material condition, tooling and forming method. A universal material-range table would hide those conditions and create false precision. Enter K as an explicit theoretical assumption, then use the optional trial record to derive an effective geometric K from your own measurements. That derived value remains user-entered and unverified; it is not a universal replacement for the next trial.

Model domain and reference rows

The forward calculator accepts bend rotation α from 1° to 179°, K from 0.20 to 0.55, and positive radius, thickness and outside dimensions within the field limits. Inverse K is retained as a diagnostic result when outside the forward range; it cannot be applied to forward mode. A result above 0.5 calls for review, not automatic replacement by 0.5.

The r/t reference rows compare 0.5, 1, 2 and 3 while holding the other inputs constant. These are geometric comparisons, not tooling recommendations. A V-die estimate does not determine the radius or K used here. Check that each outside leg reaches at least the setback s and that BA is positive before interpreting the flat diagram.

Check a separate opening estimate with the V-die opening calculator; it does not determine the inside radius for this calculation.

Close the loop with a measured trial

Use measurements from the same single-bend specimen, with no other forming or trimming. Cut and measure a trial blank, record material condition/batch, actual thickness, grain direction and punch/die IDs, then bend and measure after unloading. Record β and the inside radius separately; establish the outside virtual corner by extending the measured outer faces before recording A and B. The optional derivation computes measured BD = A + B − blank length, obtains BA from 2 × OSSB − BD, and reports effective geometric K = [180 × BA / (πα) − r] / t. Keep instrument resolution, measurement method and drawing tolerance with the record. Adjusting K cannot repair mixed angle conventions, wrong leg references or an incorrect measured radius. The default CSV remains V1; opt-in V2 separates user measurements, optional context and the derived result. Neither export automatically calibrates the machine or proves production repeatability.

Independent algebra cross-check, not a RAGOS trial: the 2015 Song Yixiang, Meng Xianli and Geng Yalin paper on K factor and bend-deduction conversion (issue 21, pages 15–16) gives r = 2 mm, t = 2 mm, β = 90° and bend deduction 3.25 mm. Recomputation gives OSSB = 4 mm, BA = 4.75 mm and effective K = 0.511971959; with A = B = 20 mm, the blank is 36.75 mm. The paper's material and machine context does not make this K a universal value or a RAGOS measurement.

For the complete preparation and confirmation process, use the trial bend guide.

Formula references and scope

The neutral-layer relationship can be checked against SOLIDWORKS Help. The following references distinguish dimensionless K, dimensional deduction and springback; their workshop settings are not universal presets. SOLIDWORKS Help: K-factor.

Song Yixiang, Meng Xianli and Geng Yalin, “Effects and conversion of bend factor K and bend deduction in sheet-metal bending” (translated title), 2015, issue 21, pp. 15–16. The published example gives K ≈ 0.511972; retain the value and check its assumptions. The article’s equation (5) uses an arc-term denominator of 90 where equation (7) uses 180; the neutral-axis derivation and final example support 180 for angles in degrees.

Zhang Pengfei, “Research on sheet-metal development technology” (translated title), Internal Combustion Engine & Parts, 2024, issue 19, pp. 105–107; DOI: 10.19475/j.cnki.issn1674-957x.2024.19.012. Its workshop “bend coefficients” are deductions measured in mm and cannot be entered directly as dimensionless K.

Zhou Yujia, Hu Fengsong and Yuan Jiajian, “Prediction and analysis of springback in V-shaped air bending of thin sheet” (translated title), Journal of Plasticity Engineering, 2023, 30(11), pp. 21–27; DOI: 10.3969/j.issn.1007-2012.2023.11.003. Its finite-element and BP models address springback under particular conditions; their reported accuracy does not describe this geometry calculator.

The literature examples are external references, not RAGOS factory trials. Validate the chosen K and flat length using the actual material and tooling before production.

To estimate forming force separately, use the press brake tonnage calculator.

Using the result in a quotation

For quotation or layout comparison, use the theoretical result with its input assumptions recorded. Use the flat length to size the blank and the bend deduction to explain a difference between a drawing dimension and a programmed blank. The pair is also useful when comparing a quoted part with an existing nested layout: if the quoted flat length differs by more than the tolerance, ask which radius, K factor and bend method were assumed. Keep the assumptions with the quotation so a later revision can be checked against them.

For later equipment selection, review MG up-acting press brakes and NG electric press brakes; this geometric result does not select a machine.

Confirm geometry and a trial bend before production

The result is an estimate for quotation preparation. Before releasing production blanks, confirm the radius, K factor and flat length with engineering and a trial bend.